2.1. Mathematical Model of Dynamic Stress–Strain State and Fracture of Steel Pipelines with Consideration of Temperature Influence
A section of length L of the main gas pipeline between two supports was considered (
Figure 1a). A pipe with a large diameter D and wall thickness H was assumed. There was a straight crack in the central part of the pipe on its outer surface. It ran in the longitudinal direction of the pipe, perpendicular to the axial section. Its initial width w did not exceed a value of 1.0 mm or an initial length of
l = 80 mm. A variant of the crack a = H was also considered, where the angle at the crack tip at the initial moment of the dynamic process was instead equal to 20° (
Figure 1b). One support implemented the conditions of rigid pipe embedment, while the other moved longitudinally. The supports were equidistant from the initial position of the crack for a long distance and did not influence the process of its development.
The variable load of the considered gas pipeline section was modeled. The internal pressure drop in the pipe during the formation of a through crack caused by gas leakage and the gas pressure on the walls of the through crack were considered.
The pipe inner surface was loaded with uniformly distributed dynamic pressure
[
20]. It was considered that the beginning of the dynamic process
t0 was the moment when the fixed operating pressure along the gas pipe began to change. The value of the dynamic pressure at any time was defined as follows [
20]:
where
is the pressure in the pipe operating until the formation of a through crack,
is the moment of time for the formation of a through crack,
is the Heaviside function, and
is the gas pressure attenuation coefficient along the pipe.
Gas-dynamic processes taking place in the vicinity of a through crack in a gas pipeline are extremely complex [
20]. A number of models of gas flow through a crack currently exist. The model that most accurately describes the process in this work is the one that considers fracture deformation because the crack can change its shape and size as the pressure changes during gas flow through a crack [
21]. At the same time, progressive uniform gas flow is disturbed in the area of the crack, and as a result, the pressure distribution in the pipe cross-section of the damage zone is not uniform. However, the major difficulty in modeling gas pressure changes in the damage zone is the impossibility of mathematically describing the processes of gas flow into the atmosphere through a formed crack due to the uncertainty of its size and topography. Consequently, it is appropriate to use a coefficient value of
based on experimental studies [
20].
The temperature effect on the dynamic deformation and local damage of the steel gas pipeline section was considered. The temperature had a major role in the process of destroying the main gas pipeline. Thus, the main effects included the following:
- -
Thermal stresses: Changes in the temperature cause the expansion and contraction of the materials that form the pipeline. This can generate stresses in the material, especially when it contains defects. Long-term thermal stresses can lead to the development of cracks and other damage.
- -
Changes in the material’s mechanical properties: When the temperature changes, the physical properties of the materials, such as their strength, elasticity, and plasticity, change. This can influence the ability of the pipeline to resist mechanical loads and deformations.
- -
Cryogenic effects: Sometimes, gases, such as liquefied natural gas, are transported at very low temperatures. This may cause cryogenic effects, such as ice formation and condensation, which can affect pipelines’ integrity.
- -
Corrosion: High or low temperatures can increase the corrosion process of the pipeline material. For instance, wet conditions at low temperatures can promote ice formation and accelerate the corrosion process.
The process of the avalanche damage in cracked sections of gas pipelines is a fast-moving process [
21]. Therefore, the long-term temperature effect in this problem can be disregarded, and only the temperature effect on the mechanical properties of the pipe material can be considered [
22]. This effect was assumed in the mathematical model of the task. Specifically, the material mechanical constants were considered as functions of the temperature: Young’s modulus
E =
E(
T), ultimate stress limit
=
, and yield strength
=
, where
is the pipe material temperature.
Movements, plastic deformations, and equivalent stresses as functions of time were determined. The material crack growth over time and local damage in the crack tip zone were analyzed. An analysis of the stress–strain state and local damage of a steel pipe section with a crack was carried out using 3D modeling.
The equations of the dynamics, excluding mass forces in a cylindrical coordinate system (
r,
φ,
z), take the following forms [
23,
24]:
where
,
, and
are the components of normal stress;
,
,
are the components of shear stress;
,
, and
are the movement components; and
is the material density. The boundary conditions were equal, as follows:
, where
is the surface of the crack edges. All remaining boundary conditions and initial conditions were instead assumed to be equal to zero. Particularly, the stress components in Equation (2) were determined depending on the deformation stage:
The problem was solved with the elastic–plastic formulation. In the elastic deformation case,
, and the dependences (3) correspond to Hooke’s law. The equation of the state under elastic deformation of a material with regard to the temperature effect is reported as follows:
, where
is Young’s modulus for a specified temperature,
is the equivalent stress, and
is the equivalent deformation. In the plastic deformation case,
. The equation of the state under plastic deformation, with the deformation rate not exceeding 10
−2 c
−1, was instead modeled using the dependence of bilinear isotropic hardening (BIH) [
25]. In this case, an equation of the state with regard to the temperature effect was as follows:
, where
is the yield strength for a specified temperature and
is the hardening modulus. In the speedy plastic deformation case,
, where
is the deformation rate. When the deformation rate exceeds the value of 10
−2 c
−1, the plastic flow of the material is described using the Cooper–Symonds model (CSS) [
25]. The use of this model allows us to take into consideration the effect of the deformation rate on the plastic flow process of the material. The equation of the state is reported as follows:
, where
is the yield strength at zero plastic deformation for a specified temperature;
B is the hardening coefficient;
is the plastic deformation;
n is the hardening index;
is the plastic deformation rate; and
D,
q are the hardening coefficients at the deformation rate. The dependencies between the deformations and displacements in a cylindrical coordinate system (
r,
φ,
z) are nonlinear [
23,
24]:
where ε
r, ε
φ, ε
z are the normal components of the deformation tensor, and γ
rφ, γ
φz, γ
rz are the tangent components of the deformation tensor. The equivalent deformations were conversely obtained by the components of the deformation tensor (4) [
21], which are described as follows:
The material damage was modeled based on a maximum stress criterion (von Mises criterion) [
26]. When the equivalent stresses exceed the limit stresses,
, local destruction of the structural material occurs [
27].
2.2. Finite-Element Model of Dynamic Stress–Strain State and Damage of a Steel Pipe Section with Regard to the Temperature Effect on the Mechanical Characteristics of the Material
A numerical solution of the problem was performed in the software package ANSYS-19.2/Explicit Dynamics. Here, spatial discretization was based on the finite-element method according to the equation of movement in the form of
where
is the mass matrix of the finite-element model,
is the vector of the generalized nodal movements of the finite-element model,
is the stiffness matrix of the finite-element model for a specified temperature, and
is the vector of forces compressed to the nodes.
The central second-order differential integration scheme was the basis for time discretization, based on which the values of accelerations, velocities, and movements were calculated as follows [
25]:
This system is steady in cases where the time integration step does not exceed
, in which
is the maximum natural frequency of the system
,
c is the sound speed in the material;
is the minimum typical size of the elements. A description of the movement of a deformed continuous environment was based on a multicomponent Lagrangian–Eulerian approach, which describes the flow of material through a grid moving in space [
25]. A one-component Lagrangian–Eulerian approach and Lagrangian formulation were also adopted. The mass matrix
in Equation (6) was achieved from an expression of the deformation of the structural elements for kinetic energy,
, where
V is the body volume and
is the material density. At finite-element discretization, the kinetic energy of deformation is reported as follows:
where
is the movement,
is the vector of the nodal movement components, and
N is the shape function matrix determining the position of the node elements. Specifically, the matrix of the element masses is equal to
The stiffness matrix
was obtained from the expression for the internal virtual work:
where
W is the internal virtual work. For a nonlinear system, potential energy accumulates over time and is usually not clearly expressed as a potential function of shift or velocity.
The Lagrange method was instead utilized to model the geometric nonlinearities. The problem was solved for a set of linearized synchronous equations with movement as the initial data were unknown for obtaining the solution at the moment of time
t + Δ
t. These synchronous equations were determined from an expression for the elements according to the principle of the virtual operation:
where
σij is the Cauchy stress tensor component,
is the deformation tensor,
ui is the deformation tensor,
xi is the current coordinate,
is the component of volumetric force,
is the component of surface forces,
V is the volume of the deformed body, and
S is the surface of a deformed body on which the load acts. The expressions for the elements were achieved with differentiation of Equation (11). The linear differential terms were kept, and all higher-order terms were neglected. Thus, a linear system of equations was obtained.
In the finite-element setting, the constitutive physical relations were used to generate a relationship between the stress increment and the deformation increment. The law only reflects the increment of stresses through strains. However, Cauchy stresses depend on the rotation of a solid body and are not invariant. Hence, an expression was used to apply the necessary stresses, such as the Yaumann velocity of Cauchy stresses, to determine the physical relations
, where
is the Yaumann velocity of Cauchy stresses,
is the rotation tensor, and
is the time derivative of Cauchy stresses. Therefore, the Cauchy stress velocity is described as follows:
Using the basic physical relations, the stress change through deformation can be expressed as
where
is the tensor of the material constants,
is the deformation velocity tensor, and
is the velocity. The Cauchy stress velocity can instead be written as
The classical setting of net movements only considers the movement or velocity as the primary unknown variables. All the other quantities, such as deformations, stresses, and state variables in the history-dependent models of materials, were obtained from the movements. This formulation is the most widely used and can cope with the most nonlinear deformation tasks. Differentiation of
allowed us to obtain the following expression:
Equation (9) was obtained as follows:
where
. Differentiation was applied as follows:
, where
ev =
eii. By substituting Equations (11) and (12) into Equation (10), the following was obtained:
The third term is asymmetric and usually insignificant in most deformation cases. Hence, it was neglected. Consequently, the final formulation of the net movement is described as follows:
The aforementioned Equation (17) is a set of linear equations with additive
Dui or variable movements that can be solved using the standard linear solutions of McMeekin and Rice [
25]. For the finite-element implementation of the general dynamic deformation model, its peculiarities should be accounted for. The limit conditions in element nodes must meet the equality of movements and their derivatives. In this case, the functions of shapes make it possible to describe a continuous and smooth change in stresses. The computational module Explicit Dynamics uses quadrilateral elements (tetrahedrons) and octahedral elements (hexahedrons) for 3D models. In this work, the hexahedral 8-node element was used, which provided equality of the movements, velocities, and accelerations at the nodes [
25]. The convergence of the calculated finite-element model of the task was verified using a standard mesh densification method [
21,
25].
2.3. Initial Data for Finite-Element Modeling
Finite-element numerical studies of the temperature effect on prolonged avalanche damage of main gas pipelines were carried out on an example of a section between the supports of the main gas pipeline “Beineu–Bozoy–Shymkent”. The distance between the supports was 36 m, while a rectilinear pipe section with a length of
L = 10 m, a pipe inner diameter of
D = 1.047 m, and a pipe wall thickness of
H = 15.9 mm was assumed. There was a rectilinear crack in the central part of the studied section (
Figure 2). Its initial width was
w = 1.0 mm, while its initial length was
l = 80 mm. A through crack with a depth of
a = H was considered. An angle at the crack top at the initial moment of time was instead equal to 20°. When constructing a finite-element model, the convergence of the solution was checked. Based on the results of this check, a grid was generated with the value of the “Element Size” parameter equal to 0.01, which is described in detail in the previous work of the authors [
21].
A section of pipe with a crack is under a load of unsteady internal pressure. The pressure variation with time was given in tabular form according to the experimental data obtained by Nordhagen et al. [
20]. A process of internal pressure changes in the pipe from the operating to the critical pressure, and the subsequent pressure drop due to the gas flow through the crack, was modeled.
Table 1 shows the estimated values of the internal pressure over time.
The pipe material was steel X70 [
28]. The steel density was taken as
= 7810 kg/m
3, and the Poisson’s ratio was
0.3. The mechanical characteristics of steel, the Young’s modulus
E, tensile strength
and yield strength
, depend on the temperature. Studies were conducted within the temperature range of −40 °C to +50 °C.
Table 2 shows the discrete values of these parameters for a specified temperature range with a step of 30 °C, which were adopted for the calculation studies. These values were gained by linear interpolation of the experimental data [
18,
29]. It is noted that X70 steel is a high-strength low-carbon micro-alloyed pipeline steel with high impact strength at low temperatures, while a temperature lower than −40 °C does not induce structural changes, leading to metal brittleness [
18,
29].